Some news about ordering at

A short update, hoping it could answer some questions people are asking themselves. This time, I ordered two different boards. One 15x10cm and one 5x5cm. I placed the order and uploaded my gerbers the 4/11/2011. As I had two different boards, I named the zips containing the gerbers with the size of the board (“10x15cm” and “5x5cm”). The shipment mail came the 11/11/2011 and the package the 18/11/2011. This time, it was sent with HK post registered airmail with a tracking number. Unfortunately, the tracking isn’t as good as the one with Chinapost (at least, with France as destination. I only had “the item left HK”). But it was fast. Also cheap, because they put the two board sets in the same box, so I only paid one dollar more (same price as one batch of 5×5 PCBs)

The small PCB had twice the same design. It seems to be OK, as long as you don’t put anything that eases the board cut (slots, holes line or V-groove):

USB Temperature Logger PCB Top

As usual (so far) the fabrication quality is excellent for the price.

USB Temperature Logger PCB Bottom

You’ll notice the slots for the USB plug. I’m using Altium and when a board has slots, it generates a separate drill file for them. I included the two files (round holes and slots) in my zip and apparently the fab managed to figure out what to do with them. Cool.

I used 0,15mm lines for some silkscreen (the rectangle around the tiny temperature sensor package). I see I should rather use 0,2mm lines instead, like for the other lines. The tracks, vias and separations have the same size like before (see my previous notes about iTeadStudio). I soldered the components, everything worked fine (at least mechanically). Except that one of the regulator packages is wrong, should be SOT233. Argh. Stupid me. (Well, better too big than too small.)

The 10x15cm PCB is a 16 input, SNMP state output board. You can configure each input to be pull-up, pull-down or current loop —active. Each input is opto-isolated, plus MOV and fuse protected. A web page allows you to configure the board (IP,SNMP and inputs), display the inputs state and the embedded temperature sensor reading. Then, you get the inputs state by SNMP polling or traps. I’ve been working on this for quite some time and it’s really cool.

I had one board extra (cool, especially I’ll use all of them this time) and I took the 100% e-test option. One board has a small offset in the holes, but still within the specs.

SNMP 16 Inputs Supervision PCB Bottom

I’ll try to make a separate post about this board if I have time.


Altium DRC settings for iTeadStudio PCB service

Just a quick informative note with my Design Rules settings for the iTead Studio PCB service, with Altium.

Altium Design Rules For iTeadStudio

Electrical Minimum Clearance: 0.2mm

Routing Width: 0.2mm

Routing Corners: 2,54, 45° (not really relevant)

Routing Vias: Minimum Diameter: 0.5mm; Minimum Via Hole Size: 0.3mm Preferred: 0.35mm

Solder Mask Expansion: 0.1mm

Power Plane Connect: Conductor Width: 0.3mm Air-Gap:0.3mm Expansion: 0.5mm

Power Plane Clearance: 0.5mm

Polygon Connect: Conductor Width: 0.3mm

Manufacturing Hole Size: Minimum: 0.3mm

Hole to Hole Clearance: 0.2mm

Minimum Solder Mask Sliver: 0.1mm

Silkscreen over Component Pads: 0.15mm (actually, should be rather 0, as the silkscreen isn’t (or shouldn’t be) printed on pads)

Silk To Silk Clearance: 0.1mm

Also, don’t forget the minimum Soldermask line width is 0.1mm (for text and drawings)


Sorry for the metrical system impaired people. As you can see, these settings are a little bit tighter than the ones specified by iTeadStudio, to go along with their “6mil (recommended >8mil)” funny sentence. Well, not really, as 0.2mm are equivalent to 7.87mils but it worked for me. Maybe the 0.35mm/0.5mm vias are borderline. If you want to be sure about the results (and not get the Fab people angry), you should make it more 0.35mm/0.6mm or 0.3mm/0.7mm, as there’s a 0.09mm tolerance in the hole registration and diameter.

For Gerber generation, I use the default settings, with the 2:3 and inches option. Don’t forget to select only the layers you use (top/bottom, Silk top/Silk bottom, Solder top/Solder bottom) and the RS274X format.

If my second batch of boards have a problem, I’ll update this post.

As last advice, I’d say to not rely on your power plane connections (if you poor a power plane on your board), but to make connections with tracks first and only then poor the power plane, so you’re sure that you’re within the minimum width/spacing specs.

Testing iTead Studio PCB service.

Few months ago, opened one of the cheapest PCB making service of the web. They claim a 6/6mil and 0,3mm hole size specs. Two layers with top and bottom silkscreen, soldermask for everyone, Woohoo! Their prices start at $12 for ten pieces of a 5x5cm PCB plus $4 shipping (in my case, to France). They even have a special offer right now at $9.90 for 10 pieces of 5x5cm PCB. And for $10 more, you get all the boards e-tested (“only” half of them are e-tested for free).

It seems like it’s not worth any more to bother with home made etching for small boards, for that price! (I pay something like 9 Euros for a 120×150 blank FR4 board (w/o shipping) and I have to make vias myself and of course, no silkscreen, no soldermask)

I needed to make a 120×150 PCB with features impossible to achieve without real vias, so I decided to test iTead Studio with a small 5x5cm board. For a long time, I also wanted to learn USB programming with PICs and to use Altium designer. Three good reasons to try the Chinese fab.

I adapted Microchip’s USB demo board schematics, the one with a 18f87J50 microcontroller and threw the components on the board (after some nights spent with Altium tutorials. Argh, libraries.)

I used the following design rules: track width: 0,2mm. Vias diam:0,5mm. Vias holes: 0,35mm. Solder mask extension:0,1mm. Minimum soldermask sliver: 0,1mm. Silk/Silk: 0,1mm. iTeadStudio advises to not go as low as 6/6mil, but try to use 8/8mil rules. Some people (like Dave Jones from had a bad experience with the fab changing his gerbers, but it was before they updated their fab rules.

After checking and double checking my gerbers (it was the first time I sent something to a fab), I ordered and paid for the 5x5x10 PCB service the 24/08/2011 @1:50pm (local times). My order was confirmed ten minutes later, with the address to send my gerbers to, what I did @ 2pm ; the two copper layers, two silk layers, two soldermask layers and the drill file, all zipped and labelled as instructed on the website. I received an answer the 25/08 @4am, saying they submitted my files to the fab and that they’ll keep me updated if there’s a problem. Apparently, my files were all right, because the next iTeadStudio mail was on the 30/08/2011 @3:30pm with a tracking number for my PCBs (I took the air mail shipping, for $4).

The tracking number worked two days later:

iTeadStudio Shipping Tracking

Actually, you only get the tracking inside China (at least in my case with France as for destination)

The package was delivered to me on the 09/09/2011. That’s one week shipping, which is really fast! As the value was small, I apparently didn’t have any trouble with French customs.

Cute Package From iTeadStudio

I got twelve PCB. Six of them have a mark on the side meaning they passed the e-test:

iTeadStudio 5x5cm PCBs

After a quick visual inspection, I noticed a suspicious track on one of the e-tested boards but I checked it myself and it’s ok. An other e-tested board has its silkscreen erased on a 1cm wide band.

e-tested board (top):

iTeadStudio PCB e-tested

(I didn’t take the time to tidy my routing as I usually do. I also forgot to configure the GND poor to integrate all the GND tracks). The board edges could be better, but maybe the rounded corners I defined were too small. I tried tenting on some vias (to see if they would make it). It worked, they’re on the extreme right side and one under the S1 switch. I didn’t try NPTH, I’ll do it next time (but I don’t see why it wouldn’t work, they’re offering to drill slots)

Here, the board with superposed picture from Altium:

iTeadStudio PCB with Altium image superposed

As you can see, there’s a tiny offset in the silk printing and the soldermask is a bit strange (it overlaps on the vias). Apart from that, it’s perfect.

Gif animation (click to open):

View of a non e-tested PCB:

iTeadStudio PCB NON e-tested

You’ll notice the shorts on the upper left corner and under S1. If it’s the only errors, it will be easy to fix.  An other non e-tested board has a line of shorts on the big chip footprint (un-fixable). Actually, it looks like a hair on the photomask 🙂

Except these two PCBs, the other non-tested ones look quite OK. I’ll check them if I have time.


Is it worth it?

I’d say YES! Even if you need only one or two boards, it’s still less pain than to etch them yourself. And you’ll have a real silkscreen, a real soldermask and real vias! Even for larger boards, it’s still worth it, in my opinion. You should maybe consider buying the $10 100% e-test when you start to exceed the 10x10cm dimensions. If you’re a hobbyist or even an advanced hobbyist, you’ll be able to have enough-quality PCBs for very cheap. If you’re a professional, maybe you should consider a fab closer from your country, one you can directly talk with, but I’d say iTeadStudio could even be used for the first prototypes. If you have time to wait for the shipping.

All in all, the fabrication and shipping took 16 days, including two weekends. It’s really not bad, but maybe I was lucky. More expensive or bigger orders could be checked more carefully by your country’s customs.

So, where’s the catch?

Well, if I look at the boards, I don’t see any catch. You get what you pay for, even a little more. There’s also SeeedStudio offering the same PCB services and some people were saying iTeadStudio and Seeed use the same fab (makes sense, same price, same options, same DRC rules). It’s the first service for proto boards with such small prices I ever see. I suspect the fab is making those PCBs at the same time as other more legit orders and uses the available room on the boards to process the prototypes. Also, they seem to print as many boards as it takes to reach the 50% OK e-test (I got 12 boards).

But once again, I base my thoughts on the only order I passed and the first one. I’ll update this article when I order more boards. And also when I’ll solder the components on the boards I just got.


[UPDATE]: See then new post about fitting components on the board.